Power PCB guide
Heavy copper PCBs for high current: copper weight, trace width and heat
Motor drivers, battery packs, chargers, LED drivers and power supplies push amps, not milliamps, through their copper. This guide explains what copper weight really means, how to size traces for current and temperature rise, what changes when you go to heavier copper, and which copper weights you can order online at Microplacer.
Get an instant quoteWhat copper weight (oz) means in thickness terms
PCB copper is specified by weight: the number of ounces of copper spread evenly over one square foot. Because the area is fixed, weight translates directly into thickness. 1 oz per square foot works out to roughly 35 µm (about 1.4 mil).
| Copper weight | Approx. thickness | Where it is typically used |
|---|---|---|
| 0.5 oz | ≈ 17–18 µm | Inner signal layers and fine-pitch routing where narrow traces must be etched accurately |
| 1 oz | ≈ 35 µm | The everyday standard for outer layers on most electronics |
| 2 oz | ≈ 70 µm | Power rails of a few amps, motor and LED drivers, better heat spreading |
| 2.5 oz | ≈ 87 µm | Higher-current outer layers on simple power boards |
| 3.5 oz | ≈ 122 µm | Battery, charger and high-current distribution boards |
| 4.5 oz | ≈ 157 µm | Busbar-like conductors on the board, very high current paths |
These are nominal values. On outer layers the finished thickness also includes the copper plated onto the surface while the holes are plated, so finished outer copper is usually a little thicker than the starting foil, and the exact figure varies between builds. The industry generally calls boards with about 3 oz or more on a layer “heavy copper”.
Why thickness matters
How current, temperature rise and trace width relate
A trace does not have a fixed “maximum current”. Current heats it (I²R loss), and the right width is the one that keeps the temperature rise within a limit you choose — commonly 10 °C for a conservative design, 20–30 °C where space is tight and the parts and laminate tolerate it.
Current
Cross-section
Allowed temperature rise
IPC-2152 is the current IPC reference for sizing conductors for current. It is based on measured data and takes into account things the older charts ignored, such as board thickness and nearby copper planes that pull heat away. Its predecessor, the chart in IPC-2221, is still widely used as a quick, conservative estimate. The table below uses that classic formula for an outer-layer trace with a 10 °C rise — treat it as a starting point, then check your final widths with an IPC-2152-based calculator.
| Current | 1 oz outer trace | 2 oz outer trace | 3.5 oz outer trace |
|---|---|---|---|
| 1 A | ≈ 0.3 mm | ≈ 0.15 mm | ≈ 0.1 mm (often limited by the minimum width heavy copper can be etched to) |
| 2 A | ≈ 0.8 mm | ≈ 0.4 mm | ≈ 0.2 mm |
| 3 A | ≈ 1.4 mm | ≈ 0.7 mm | ≈ 0.4 mm |
| 5 A | ≈ 2.8 mm | ≈ 1.4 mm | ≈ 0.8 mm |
| 10 A | ≈ 7.2 mm | ≈ 3.6 mm | ≈ 2.1 mm |
General guidance only, rounded, for a single isolated trace in still air. Real boards often run cooler (planes and pours spread heat) or hotter (enclosed boxes, neighbouring hot parts, many loaded traces side by side). Always allow margin for peak and inrush current, not just the average.
- 1
Find the worst-case continuous current
Use the real RMS current of each net, including the highest load, lowest input voltage (for converters) and any long-duration peaks. - 2
Pick an allowed temperature rise
Start from the maximum ambient inside your enclosure and the hottest temperature the board and nearby components may reach. 10 °C is a common, comfortable choice. - 3
Choose the copper weight
Decide this before routing. If the required widths at 1 oz will not fit, move the power layer to 2 oz or heavier instead of squeezing traces. - 4
Calculate the width and check voltage drop
Wide traces can still drop noticeable voltage over a long run. Check the IR drop against the tolerance of the load, especially on low-voltage rails.Tip: Copper resistance rises with temperature — roughly 0.4% per °C — so hot traces drop more voltage than a room-temperature calculation shows.
- 5
Review the hot spots
Necks where a wide trace squeezes between pads, thin connections into a connector pin and single vias are where heat concentrates. Fix those first.
Outer vs inner layers: why inner traces carry less current for the same width
An outer trace can lose heat straight into the air (and through the solder mask). An inner trace is buried in glass-epoxy, which conducts heat poorly, so it must push its heat through the laminate before it can escape.
| Outer layer | Inner layer | |
|---|---|---|
| How heat escapes | Convection and radiation from the surface, plus conduction into the board | Only by conduction through dielectric to the surface or to nearby planes |
| Classic IPC-2221 view | Baseline | About half the current for the same cross-section — inner traces needed roughly 2.6× the cross-section for the same current |
| IPC-2152 view | Depends on board thickness and nearby planes | Often closer to outer-layer performance than the old chart suggests, especially next to a solid copper plane |
| Practical rule | Use the outer-layer numbers | Size conservatively (wider) unless you have done an IPC-2152-based calculation for your stack-up |
Inner copper on a multilayer board is usually thinner than outer copper, which makes the difference larger. A good layout puts the heaviest currents on outer layers, or on an inner plane with a large area, and uses inner layers for wide pours rather than narrow power traces. How layers are arranged is covered in the stack-up and impedance guide.
Copper weights our online calculator offers
These are the copper choices our online calculator offers for instant pricing. Choose the weight in the “High-spec options” section of the quote form.
| Board type | Outer copper (oz) | Inner copper (oz) |
|---|---|---|
| Rigid FR-4, 1 layer | 1, 2 | — |
| Rigid FR-4, 2 layers | 1, 2, 2.5, 3.5, 4.5 | — |
| Rigid FR-4, 4 to 16 layers | 1, 2 | 0.5, 1, 2 |
| Flexible, 1–2 layers | ⅓, ½ or 1 — set by the flex thickness you choose | — |
Instant online price
Quoted by our team
Copper weight interacts with other options, such as board thickness and impedance. See the full list of choices on the PCB capabilities page and in the materials and thickness guide.
How heavy copper changes minimum trace and space and the etching process
Copper is removed by chemical etching. The etchant works downward through the copper, but it also eats sideways under the edge of the etch resist (undercut). The thicker the copper, the longer the etch, and the more sideways loss.
Trapezoid, not rectangle
Wider gaps are needed
Finer features suffer first
| Copper weight | Typical industry minimum trace / space (general guidance) | Design advice |
|---|---|---|
| 1 oz | Around 0.1–0.15 mm | Comfortable for most mixed signal and power designs |
| 2 oz | Around 0.15–0.2 mm | Give fine-pitch ICs extra room; keep signal traces short and simple |
| 3–4.5 oz | Around 0.25–0.4 mm and up | Use generous gaps; avoid fine-pitch parts on the heavy-copper layer if you can |
These ranges are common across the industry, not Microplacer limits. Our engineers check every file before production and contact you if a gap or trace is too tight for the copper weight you chose. General width, spacing and clearance rules are in the PCB design rules guide.
Thick copper also needs more resin and mask
Carrying current between layers: via arrays
A via is a short copper tube. Its current capacity depends on the plated wall thickness and the hole diameter, not on the copper weight of the layers it connects — so a single via is often the weakest link in a heavy-copper path.
| Via drill | Rough continuous current per via (general guidance) | Notes |
|---|---|---|
| 0.3 mm | On the order of 1 A | Plated wall is typically about 20–25 µm thick, much thinner than heavy outer copper |
| 0.5 mm | On the order of 1.5–2 A | Larger circumference gives more wall copper |
| 1.0 mm | On the order of 3 A | Useful for power transfer; check pad size and spacing |
Rough estimates for a modest temperature rise. Vias are short and connect to large copper areas that draw heat away, so they often run cooler than a trace of the same cross-section — but plating thickness varies, so design with margin.
- 1
Divide the current
Estimate the current per via, then use enough vias in parallel to stay comfortably below it — for example, at least 5–6 small vias for a 5 A path. - 2
Spread them across the path
Place vias across the full width of the trace or pour, not in a single line at one edge, so the current shares evenly. - 3
Keep them near the load
Put the via array close to where current enters or leaves the layer to keep the path short. - 4
Watch thermal reliefs
Solid via connections into planes carry the most current; thermal spokes reduce it. Use solid connections for power vias that are not soldered.Tip: Vias in pads and under parts may need plugging or filling — see the vias guide.
Via types, plugging and filling options are explained in the vias and special holes guide.
Power-board layout tips
Copper weight is only half the job. Layout decides whether the current actually flows where you planned.
Use pours, not traces
Short and direct
Mind the bottlenecks
Connector pins and pads
Use both sides
Separate power and signal
Spread the heat
Respect voltage spacing
Think about assembly
Cost and lead-time impact of heavier copper
Heavier copper costs more for clear reasons: more copper material, longer plating and etching, more careful lamination and more inspection.
| Factor | What changes with heavier copper |
|---|---|
| Material | Thicker foil and laminate with heavy copper cost more than standard 1 oz material. |
| Process time | Etching, plating and lamination cycles take longer, and some steps may be repeated. |
| Yield | Tighter features on thick copper are harder to build, so design margin directly helps price. |
| Lead time | Heavier copper can add production steps and time; if your schedule is tight, ask our team before ordering. |
The cheapest way to carry current is often a smart layout on standard copper — wider pours, both layers in parallel, shorter paths. Move to heavier copper when the space is truly limited. Our calculator updates the price instantly when you change copper weight, so you can compare options before you order. More on what drives price in PCB cost factors.
What to specify when ordering heavy copper
A clear order avoids questions and delays. Include the following in your files or in the note field of the order form.
| Item | What to tell us |
|---|---|
| Copper weight per layer | Outer and inner copper weight, matching the values used in your design rules and calculations. |
| Finished thickness requirement | Say whether your oz value is the starting foil or the finished copper you need, if it matters for your design. |
| High-current nets | Which nets carry high current and the expected current, so our engineers can pay attention to them. |
| Board thickness and layer count | The same values as in your Gerber files and stack-up. |
| Voltage and spacing needs | Any working voltage, creepage or clearance requirement from your product standard. |
| Assembly needs | If we also assemble the board, mention heavy-copper pads on large pours and any press-fit or high-current connectors. |
How to package Gerbers, drill files, readmes and notes is explained in Preparing your design files.
How ordering works at Microplacer
Heavy copper FAQ
Related guides
Still have a question?
Send us your files or call us — our engineers will help you choose the right options for your boards and assembly.
Streamline your innovation with
seamless PCB ordering.